Next: Example Model CPE8 Up: Example Models Previous: Example Models
Next: Example Model CPE8
Up: Example Models
Previous: Example Models
This example illustrates the creation of a box-section cantilever beam with a single point load at the free end. Gravitational forces are not modelled.
PROPERTY FE-PROG ABAQUS GEOMETRY POINT P1 0 GEOMETRY POINT P2 100 PROPERTY MAT MAT STEM 210E3 0.29 0.786E-5 0.15E-4 293 PROPERTY PHYSICAL BOX PH1 10.0 8.0 1.0 2.0 PROPERTY PHYSICAL BOX PH1 ORIENT 0 0 1 GEOMETRY LINE L1 P1 P2 20 MESHING TYPE L1 BE2 12 PROPERTY ATTACH L1 STEM PH1 PROPERTY LOAD FORCE P2 -100.0 2 PROPERTY BOUNDARY CONSTRAINT P1 9 MESHING GENERATE UTILITY WRITE ABAQUS b31box.inp YES
**********************************************
** ABAQUS 5.2 INPUT DECK *
** CREATED BY FEMGEN/FEMVIEW VERSION 2.305 *
** TRANSLATED BY FEMGEN-ABAQUS VERSION 3.000 *
** FILE CREATED: DATE 06/04/94 TIME 15:22:59 *
**********************************************
**
**********************************************
** BINARY RESULT FILE FORMAT SELECTED *
** MESSAGE LOGGING IS OFF *
** DIALOG SESSION IS OFF *
** ABAQUS/Standard SELECTED *
** EXTERNAL MATERIAL DIRECTORY NOT USED *
** EXTERNAL RESULT OUTPUT FILE NOT USED *
**********************************************
**
*HEADING
FEMGEN MODEL B31BOX TRANSLATED BY PRE-ABAQUS 3.000 TITLE: No model title
**
**********************************************
** MODEL DEFINITION ... *
**********************************************
**
*******************
** MODEL GEOMETRY *
*******************
**
*NODE, NSET=ALLNODE
1, 0.0000000 , 0.0000000 , 0.0000000
2, 5.000000 , 0.0000000 , 0.0000000
3, 10.00000 , 0.0000000 , 0.0000000
4, 15.00000 , 0.0000000 , 0.0000000
5, 20.00000 , 0.0000000 , 0.0000000
6, 25.00000 , 0.0000000 , 0.0000000
7, 30.00000 , 0.0000000 , 0.0000000
8, 35.00000 , 0.0000000 , 0.0000000
9, 40.00000 , 0.0000000 , 0.0000000
10, 45.00000 , 0.0000000 , 0.0000000
11, 50.00000 , 0.0000000 , 0.0000000
12, 55.00000 , 0.0000000 , 0.0000000
13, 60.00000 , 0.0000000 , 0.0000000
14, 65.00000 , 0.0000000 , 0.0000000
15, 70.00000 , 0.0000000 , 0.0000000
16, 75.00000 , 0.0000000 , 0.0000000
17, 80.00000 , 0.0000000 , 0.0000000
18, 85.00000 , 0.0000000 , 0.0000000
19, 90.00000 , 0.0000000 , 0.0000000
20, 95.00000 , 0.0000000 , 0.0000000
21, 100.0000 , 0.0000000 , 0.0000000
*ELEMENT, TYPE=B31 , ELSET=L1
1 1 2
2 2 3
3 3 4
4 4 5
5 5 6
6 6 7
7 7 8
8 8 9
9 9 10
10 10 11
11 11 12
12 12 13
13 13 14
14 14 15
15 15 16
16 16 17
17 17 18
18 18 19
19 19 20
20 20 21
**
********************
** SET DEFINITIONS *
********************
**
*ELSET, ELSET=PHY1
L1 ,
*ELSET, ELSET=ALL
PHY1 ,
**
*************************
** PROPERTY DEFINITIONS *
*************************
**
*BEAM SECTION, SECTION=BOX , ELSET=PHY1 ,MATERIAL= STEM
8.000 , 10.00 , 1.000 , 2.000 , 1.000 , 2.000
0.0000 ,0.0000 , 1.000
**
*************************
** MATERIAL DEFINITIONS *
*************************
**
*MATERIAL, NAME=STEM
*DENSITY
0.7860001E-05,
*ELASTIC, TYPE=ISO
210.0E+03,0.290 , 293.
*EXPANSION, ZERO= 293.0000
0.1500000E-04, 293.0000
**
**************************
** KINEMATIC CONSTRAINTS *
**************************
**
*NSET, NSET=P1
1
*BOUNDARY
P1 , 1, 6
**
**********************************************
** HISTORY DEFINITION ... *
**********************************************
**
**********************************************
** FEMGEN LOADCASE 1 *
**************************
**
*STEP, PERTURBATION
*STATIC
*NSET, NSET=P2
21
*CLOAD, OP=NEW
P2 , 2 , -100.0000
**
***************************
** RESULTS OUTPUT CONTROL *
***************************
**
*NODE FILE
U
*EL FILE, POSITION=AVERAGED AT NODES
S,E
*EL FILE, POSITION=NODES
S,E
*EL FILE, POSITION=INTEGRATION POINTS
S,COORD
E,COORD
*END STEP
**
**********************************************